PartDesign PolarPattern

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PartDesign PolarPattern

Menu location
Part Design → Apply a pattern → PolarPattern
Workbenches
PartDesign
Default shortcut
None
Introduced in version
-
See also
None

Description

The PartDesign PolarPattern tool creates a polar pattern of one or more features.

A slot-shaped pocket (B) made on top of a base solid (A, also referred to as support) is used for a polar pattern. The result (C) is shown on the right.

Usage

  1. Optionally activate the correct Body.
  2. Optionally select one or more features.
  3. There are several ways to invoke the tool:
    • Press the PolarPattern button.
    • Select the Part Design → Apply a pattern → PolarPattern option from the menu.
  4. If there is no active Body, and there are two or more Bodies in the document, the Active Body Required dialog will open and prompt you to activate one. If there is a single Body it will be activated automatically.
  5. If no features were selected the Select feature task panel opens: select one or more (hold down the Ctrl key) from the list and press the OK button.
  6. The PolarPatternparameters task panel opens. See Options for more information.
  7. Press the OK button to finish.

Options

  • To add features:
    1. Press the Add feature button.
    2. Select a feature in the Tree view or the 3D view.
    3. Repeat to add other features.
  • To remove features:
    1. Press the Remove feature button.
    2. Do one of the following:
      • Select a feature in the Tree view or the 3D view.
      • Select a feature in the list and press the Del key, or right-click and select Remove from the context menu.
    3. Repeat to remove other features.
  • If there are several features in the pattern, their order can be important. See Ordering features.
  • Specify the pattern Axis:
    • Normal sketch axis: The Z axis of the sketch (only available for sketch-based features).
    • Vertical sketch axis: The Y axis of the sketch (idem).
    • Horizontal sketch axis: The X axis of the sketch (idem).
    • Construction line #: The construction lines in the sketch, if any (idem).
    • Base X axis: The X axis of the Body.
    • Base Y axis: The Y axis of the Body.
    • Base Z axis: The Z axis of the Body.
    • Select reference...: Select a Datum Line in the Tree view or a Datum Line or edge or in the 3D view.
  • Check the Reverse direction checkbox to reverse the pattern.
  • Specify the Angle to be covered by the pattern.
  • Specify the number of Occurrences (including the original feature).
  • If the Update view checkbox is checked the view will update in real time.

Ordering features

If some of the selected features are additive and others subtractive, their order can have have an impact on the final result. You can change the order by dragging a feature in the list. introduced in version 0.19

Effect of the feature order

Limitations