PartDesign MultiTransform
PartDesign MultiTransform |
Menu location |
---|
Part Design → Apply a pattern → Create MultiTransform |
Workbenches |
PartDesign |
Default shortcut |
None |
Introduced in version |
- |
See also |
PartDesign Mirrored, PartDesign LinearPattern, PartDesign PolarPattern, PartDesign Scaled |
Description
'Make a pattern from combinations of transformations' - The MultiTransform tool takes one (or a set of) part 'features' as its input, and allows the user to apply multiple transformations to that feature (or set of features) progressively, in sequence - creating a combined or compound transformation.
For example, to produce the flange with a double row of holes as pictured below, the user:
- selected the hole as the 'feature' (base) in the Model tree
- clicked on the MultiTransform icon
- added a linear pattern with two occurrences in the X direction
- added a polar pattern with eight occurrences around the Y axis.
Flange with double row of holes. Hole pattern created with 'MultiTransform' tool.
Usage
Create
- Optionally activate the correct Body.
- Optionally select one or more features in the Tree view or the 3D view.
- There are several ways to invoke the tool:
- Press the MultiTransform button.
- Select the Part Design → Apply a pattern → MultiTransform option from the menu.
- If there is no active Body, and there are two or more Bodies in the document, the Active Body Required dialog will open and prompt you to activate one. If there is a single Body it will be activated automatically.
- If no features were selected the Select feature task panel opens: select one or more (hold down the Ctrl key) from the list and press the OK button.
- The MultiTransform parameters task panel opens. See Options for more information.
- Press the OK button at the top to finish.
Edit
- Do one of the following:
- The MultiTransform parameters task panel opens. See Options for more information.
- Press the OK button at the top to finish.
Combine existing transformations
It is possible to create a MultiTransform object from existing Mirrored, LinearPattern and PolarPattern transformations.
- Check the DataOriginals property of the existing transformations to make sure they have been applied to the same features.
- Select those features in the Tree view.
- There are several ways to invoke the tool:
- Press the MultiTransform button.
- Select the Part Design → Apply a pattern → MultiTransform option from the menu.
- The MultiTransform parameters task panel opens.
- Press the OK button at the top.
Alternate Method 1
This method starts with one existing transformation feature in the Body object.
- In the Model tree, within the active Body object, select the existing features to be included.
- Click on the MultiTransform icon to initiate the operation.
- In the feature list view, you will see the label(s) of the previously selected feature(s).
To add additional features, see Step 3 in the Standard Method above. - Finish using Steps 5-8 in the Standard Method above.
Alternate Method 2
This method starts with multiple existing, independent feature transformations in the Body object - with the idea of combining them. NOTE: to combine existing transformations, they must be within the same Body object and should all use the same feature or feature set in each.
- In the Model tree, within the active Body object, select one of existing transformation of those you wish to include.
- Click on the MultiTransform icon to initiate the operation.
- Click the OK button at top to save and exit.
- In the object tree, select the newly created MultiTransform.
- In the Property View window, locate the Transformations property in the Data tab.
- Edit the Transformations property by clicking on its value, then click on the ellipse box that appeared to open the Links window for this property.
- Select all existing feature transformations that should be included. Multiple selections are permitted using CTRL + click.
- Click OK to save and close the Links window.
- Click the Refresh button if activated.
When initiated and completed in this way, the MultiTransform might fail to become the "Tip" of the Body object. If you need it to be the "Tip":
- Right click on the newly created MultiTransform.
- If available, choose "Set tip".
Options
- To add features:
- To remove features:
- To add transformations:
- Right-click the Transformations list.
- Select one the available options from the context menu:
- Add mirrored transformation. See PartDesign Mirrored.
- Add linear pattern. See PartDesign LinearPattern.
- Add polar pattern See PartDesign PolarPattern.
- Add scaled transformation. See PartDesign Scaled.
- The selected transformation is added to the list and the settings for the transformation are displayed below the list.
- Adjust the settings to suit.
- Press the OK bar at the bottom.
- Repeat to add more transformations.
- To edit a transformation:
- Right-click the transformation in the Transformations list.
- Select Edit from the context menu.
- Adjust the settings to suit.
- Press the OK bar at the bottom.
- To change the order of the transformations:
- Right-click a transformation in the Transformations list.
- Select Move up or Move down from the context menu.
Usage Notes
- Supported feature transformations are: Mirrored, Linear Pattern, Polar Pattern, and Scaled transformation.
- Each transformation linked to the MultiTransform should use the same feature, or set of features, in each.
Limitations
- Structure tools: Part, Group
- Helper tools: Create body, Create sketch, Attach sketch, Edit sketch, Validate sketch, Check geometry, Create a sub-object(s) shape binder, Create a clone, Create a datum plane, Create a datum line, Create a datum point, Create a local coordinate system
- Modeling tools:
- Additive tools: Pad, Revolution, Additive loft, Additive pipe, Additive helix, Additive box, Additive cylinder, Additive sphere, Additive cone, Additive ellipsoid, Additive torus, Additive prism, Additive wedge
- Subtractive tools: Pocket, Hole, Groove, Subtractive loft, Subtractive pipe, Subtractive helix, Subtractive box, Subtractive cylinder, Subtractive sphere, Subtractive cone, Subtractive ellipsoid, Subtractive torus, Subtractive prism, Subtractive wedge
- Boolean: Boolean operation
- Dress-up tools: Fillet, Chamfer, Draft, Thickness
- Transformation tools: Mirrored, Linear Pattern, Polar Pattern, Create MultiTransform, Scaled
- Extras: Migrate, Sprocket, Involute gear, Shaft design wizard
- Context menu: Set tip, Move object to other body, Move object after other object, Appearance, Color per face
- Preferences: Preferences, Fine tuning
- Getting started
- Installation: Download, Windows, Linux, Mac, Additional components, Docker, AppImage, Ubuntu Snap
- Basics: About FreeCAD, Interface, Mouse navigation, Selection methods, Object name, Preferences, Workbenches, Document structure, Properties, Help FreeCAD, Donate
- Help: Tutorials, Video tutorials
- Workbenches: Std Base, Assembly, BIM, CAM, Draft, FEM, Inspection, Material, Mesh, OpenSCAD, Part, PartDesign, Points, Reverse Engineering, Robot, Sketcher, Spreadsheet, Surface, TechDraw, Test Framework
- Hubs: User hub, Power users hub, Developer hub