PartDesign Chamfer
PartDesign Chamfer |
Menu location |
---|
Part Design → Apply a dress-up feature → Chamfer |
Workbenches |
PartDesign |
Default shortcut |
None |
Introduced in version |
- |
See also |
PartDesign Fillet |
Description
The PartDesign Chamfer command creates chamfers on the selected edges of an object. It adds a Chamfer object to the document with its corresponding representation in the Tree view.
Usage
Add a chamfer
- Make sure the correct body is active. If required double-click it in the Tree view.
- There are several ways to select the edges to chamfer:
- Select one or more edges of the active Body individually.
- Select one or more faces of the active Body to select all their edges.
- Select a feature (usually the last feature) of the active Body to select all its edges. introduced in version 0.20
- For a chain of tangentially connected edges only a single edge needs to be selected, the chamfer will propagate along the chain.
- There are several ways to invoke the Chamfer command:
- Press the Chamfer button.
- Select the Part Design → Apply a dress-up feature → Chamfer option from the menu.
- If there was no active Body, and there are two or more bodies in the document, the Active Body Required dialog will open prompting you to select one.
- The Chamfer parameters task panel opens. See Options for more information.
- Press the OK button to finish the command.
Edit a chamfer
- Do one of the following:
- The Chamfer parameters task panel opens. See Options for more information.
- Press the OK button to finish the command.
Options
- To add edges do one of the following:
- Press the Add button to start selecting edges and/or faces in the 3D view.
- To select all remaining edges do the following:
- If required press the Add button.
- Use the Ctrl+Shift+A shortcut, or right-click the list and select Add all edges from the context menu. introduced in version 0.20
- To remove edges do one of the following:
- Press the Remove button to start deselecting edges and/or faces in the 3D view. Selected elements are highlighted in purple.
- Select one or more elements in the list and press the DEL key, or right-click the list and select Remove from the context menu.
- Type: Choose a chamfer type:
- Equal distance: One distance is used to place both chamfer edges.
- Two distances: Two distances are used to place the chamfer edges. introduced in version 0.19
- Distance and angle: A distance is used to place one chamfer edge, the placement of the other chamfer edge is defined by the angle of the chamfer. introduced in version 0.19
- Press the Flip direction button to flip the direction of the chamfer (deactivated for Equal distance). introduced in version 0.19
- Set the Size of the chamfer.
- Set the Size2 of the chamfer (only available if Two distances is selected).
- Set the Angle of the chamfer (only available if Distance and angle is selected).
- Check the Use all edges checkbox to select all edges. This deactivates the selection list and the related buttons. introduced in version 0.20
Notes
- PartDesign Chamfer should not be confused with Part Chamfer. Unless you know what you are doing, Part Chamfer should not be used on a PartDesign Body. See Part and PartDesign.
- Chamfers cannot completely consume the adjacent faces.
Properties
See also: Property editor.
A PartDesign Chamfer object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:
Data
Base
- DataBase (
LinkSub
): Base. Sub-link to the parent feature's list of selected edges and faces. - DataSupportTransform (
Bool
): Support Transform. "Include the base additive/subtractive shape when used in pattern features.
- If disabled, only the dressed part of the shape is used for patterning. Default:
false
.
- Data (hidden)AddSubShape (
PartShape
): Add Sub Shape. - Data (hidden)BaseFeature (
Link
): Base Feature. Link to the parent feature. - Data (hidden)_Body (
LinkHidden
): _Body. Hidden link to the parent body.
Chamfer
- DataCamferType (
Enumeration
): Chamfer Type. "Type of chamfer".Equal distance
(default),Two distances
. - DataSize (
QuantityConstraint
): Size. "Size of chamfer". Default:1,00 mm
. - DataSize2 (
QuantityConstraint
): Size2. "Second size of chamfer". Default:1,00 mm
. - DataAngle (
Angle
): Angle. "Angle of chamfer". Default:45,00 °
. - DataFlipDirection (
Bool
): Flip Direction. "Flip direction". Default:false
. - DataUseAllEdges (
Bool
): Use All Edges. "Chamfer all edges iftrue
, else use only those edges in Base property.
- If
true
, then this overrides any edge changes made to the Base property or in the dialog". Default:false
.
Part Design
- DataRefine (
Bool
): "Refine shape (clean up redundant edges) after adding/subtracting". Default:true
.
Known issues
See PartDesign Fillet.
PartDesign
- Structure tools: Part, Group
- Helper tools: Create body, Create sketch, Edit sketch, Map sketch to face
- Modeling tools
- Datum tools: Create a datum point, Create a datum line, Create a datum plane, Create a local coordinate system, Create a shape binder, Create a sub-object(s) shape binder, Create a clone
- Additive tools: Pad, Revolution, Additive loft, Additive pipe, Additive helix, Additive box, Additive cylinder, Additive sphere, Additive cone, Additive ellipsoid, Additive torus, Additive prism, Additive wedge
- Subtractive tools: Pocket, Hole, Groove, Subtractive loft, Subtractive pipe, Subtractive helix, Subtractive box, Subtractive cylinder, Subtractive sphere, Subtractive cone, Subtractive ellipsoid, Subtractive torus, Subtractive prism, Subtractive wedge
- Transformation tools: Mirrored, Linear Pattern, Polar Pattern, Create MultiTransform, Scaled
- Dress-up tools: Fillet, Chamfer, Draft, Thickness
- Boolean: Boolean operation
- Extras: Migrate, Sprocket, Involute gear, Shaft design wizard
- Context menu: Set tip, Move object to other body, Move object after other object, Appearance, Color per face
User documentation
- Getting started
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