PartDesign Chamfer
PartDesign Chamfer |
Menu location |
---|
Part Design → Apply a dress-up feature → Chamfer |
Workbenches |
PartDesign |
Default shortcut |
None |
Introduced in version |
- |
See also |
PartDesign Fillet |
Description
The PartDesign Chamfer command creates chamfers on the selected edges of an object. It adds a Chamfer object to the document with its corresponding representation in the Tree view.
Usage
Add a chamfer
- Make sure the correct body is active. If required double-click it in the Tree view.
- There are several ways to select the edges to chamfer:
- Select one or more edges of the active Body individually.
- Select one or more faces of the active Body to select all their edges.
- Select a feature (usually the last feature) of the active Body to select all its edges. introduced in version 0.20
- For a chain of tangentially connected edges only a single edge needs to be selected, the chamfer will propagate along the chain.
- There are several ways to invoke the Chamfer command:
- Press the Chamfer button.
- Select the Part Design → Apply a dress-up feature → Chamfer option from the menu.
- If there was no active Body, and there are two or more bodies in the document, the Active Body Required dialog will open prompting you to select one.
- The Chamfer parameters task panel opens. See Options for more information.
- Press the OK button to finish the command.
Edit a chamfer
- Do one of the following:
- The Chamfer parameters task panel opens. See Options for more information.
- Press the OK button to finish the command.
Options
- Type: Choose one of the Chamfer types:
- Equal distance: The chamfer edges are equally distanced from the body edge.
- Two distances: The distances of the chamfer edge to the body edge are specified. introduced in version 0.19
- Distance and angle: One distances of the chamfer edge to the body edge is specified. The second chamfer edge is defined by the angle of the chamfer. introduced in version 0.19
- Flip direction: The distance direction can be flipped using the Flip direction button (deactivated for Equal distance). introduced in version 0.19
- Size, Size2, Angle: Set the chamfer Size, and Size2 or Angle either by editing the value or by clicking on the up/down arrows.
- Size2 is only available when Two distances is selected and Angle only when Distance and angle is selected.
- Add: Add edges to the selection by pressing the Add button and selecting more edges or faces.
- To select all remaining edges right-click in the list and select Add all edges from the context menu. introduced in version 0.20
- Remove: Choose a way to remove edges from the selection:
- Select each edge or face in the list of the dialog and press the DEL key or right-click in the list and select Remove from the context menu.
- Press the Remove button. All edges and faces being previously selected are highlighted in purple. Select each edge or face to be removed.
- Since there must be at least one edge for the feature, the last remaining edge or face in the list cannot be removed.
- Use all edges: Select all edges by checking the Use all edges checkbox introduced in version 0.20. This deactivates the selection list and the related buttons.
Notes
- PartDesign Chamfer should not be confused with Part Chamfer. Unless you know what you are doing, Part Chamfer should not be used on a PartDesign Body. See Part and PartDesign.
- Chamfers cannot completely consume the adjacent faces.
Properties
See also: Property editor.
A PartDesign Chamfer object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:
Data
Base
- DataBase (
LinkSub
): Base. Sub-link to the parent feature's list of selected edges and faces. - DataSupportTransform (
Bool
): Support Transform. "Include the base additive/subtractive shape when used in pattern features.
- If disabled, only the dressed part of the shape is used for patterning. Default:
false
.
- Data (hidden)AddSubShape (
PartShape
): Add Sub Shape. - Data (hidden)BaseFeature (
Link
): Base Feature. Link to the parent feature. - Data (hidden)_Body (
LinkHidden
): _Body. Hidden link to the parent body.
Chamfer
- DataCamferType (
Enumeration
): Chamfer Type. "Type of chamfer".Equal distance
(default),Two distances
. - DataSize (
QuantityConstraint
): Size. "Size of chamfer". Default:1,00 mm
. - DataSize2 (
QuantityConstraint
): Size2. "Second size of chamfer". Default:1,00 mm
. - DataAngle (
Angle
): Angle. "Angle of chamfer". Default:45,00 °
. - DataFlipDirection (
Bool
): Flip Direction. "Flip direction". Default:false
. - DataUseAllEdges (
Bool
): Use All Edges. "Chamfer all edges iftrue
, else use only those edges in Base property.
- If
true
, then this overrides any edge changes made to the Base property or in the dialog". Default:false
.
Part Design
- DataRefine (
Bool
): "Refine shape (clean up redundant edges) after adding/subtracting". Default:true
.
Known issues
See PartDesign Fillet.
PartDesign
- Structure tools: Part, Group
- Helper tools: Create body, Create sketch, Edit sketch, Map sketch to face
- Modeling tools
- Datum tools: Create a datum point, Create a datum line, Create a datum plane, Create a local coordinate system, Create a shape binder, Create a sub-object(s) shape binder, Create a clone
- Additive tools: Pad, Revolution, Additive loft, Additive pipe, Additive helix, Additive box, Additive cylinder, Additive sphere, Additive cone, Additive ellipsoid, Additive torus, Additive prism, Additive wedge
- Subtractive tools: Pocket, Hole, Groove, Subtractive loft, Subtractive pipe, Subtractive helix, Subtractive box, Subtractive cylinder, Subtractive sphere, Subtractive cone, Subtractive ellipsoid, Subtractive torus, Subtractive prism, Subtractive wedge
- Transformation tools: Mirrored, Linear Pattern, Polar Pattern, Create MultiTransform, Scaled
- Dress-up tools: Fillet, Chamfer, Draft, Thickness
- Boolean: Boolean operation
- Extras: Migrate, Sprocket, Involute gear, Shaft design wizard
- Context menu: Set tip, Move object to other body, Move object after other object, Appearance, Color per face
User documentation
- Getting started
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