SheetMetal AddWall

Description
The SheetMetal AddWall command creates a bend on a selected edge.



Usage
To add a Bend:
 * 1) Switch to the [[Image:Sheetmetal_workbench_icon.svg|22px]] SheetMetal Workbench.
 * 2) Start with a base plate or sheet, select one or more edges to receive a bend.
 * 3) Click on the [[Image:SheetMetal_Bend.svg|24px]] Bend tool to add a bend.

Alternatively you can generate a base plate with one of the following methods as well:
 * To create a base plate use a closed 2D outline - preferably a Sketcher_NewSketch.svg Sketch - with the [[Image:SheetMetal_AddBase.svg|24px]] Make Base Wall command.
 * Method 1: Part_Box.svg Part Cube
 * Method 2: An extruded solid made with Part_Extrude.svg Part Extrude from either a:
 * Draft_Rectangle.svg Draft Rectangle or a
 * Draft_Wire.svg Draft Wire or a
 * Sketcher_NewSketch.svg Sketch
 * Use [[Image:Part_Thickness.svg|24px]] Part Thickness to create shell
 * Method 3: PartDesign_Body.svg PartDesign Body containing either an
 * PartDesign_AdditiveBox.svg additive box or a
 * PartDesign_Pad.svg PartDesign Pad made from a Sketcher_NewSketch.svg Sketch.
 * Use PartDesign Thickness.svg PartDesign Thickness to create shell


 * If you start with a PartDesign_Body.svg PartDesign Body, you can mix Sheet Metal features with PartDesign features such as PartDesign_Pocket.svg pockets or PartDesign_Hole.svg holes.

Data

 * : User name of the object in the Tree view.


 * : Bend angle.
 * : Extends the wall on the left side.
 * : Extends the wall on the right side.
 * : Gap from the left side.
 * : Gap from the right side.
 * : Invert bend direction.
 * : Length of the wall.
 * : Bend miter angle on the left side.
 * : Bend miter angle on the right side.
 * : Bend radius.
 * : Rectangle or Round. Enabled only when a gap value is set.
 * : Relief depth. Enabled only when a gap value is set.
 * : Relief width. Enabled only when a gap value is set.
 * : K factor (also known as neutral factor) for the bend. Used to calculate bend allowance when unfolding.
 * : False (default) or True. If true, unfolds the bend.

Preparation
This tray is made of a rectangular blank with walls added to its outline edges. And so one outline sketch for the blank has to be prepared in advance.



Workflow

 * 1) Create a blank
 * 2) Select the outline sketch [[Image:SheetMetal_AddWall-03.png|240px]]
 * 3) Press the  button or use the keyboard shortcut:  then  [[Image:SheetMetal_AddWall-04.png|240px]] (The blank is padded in z direction
 * 4) Add walls to the outline edges
 * 5) Select the blank's outline edges [[Image:SheetMetal_AddWall-05.png|240px]]
 * 6) Press the  button or use the keyboard shortcut:  [[Image:SheetMetal_AddWall-06.png|240px]]
 * 7) If the fold is 90° down set the value of invert property to true to reverse the direction (and length to a lower value for smaller walls) [[Image:SheetMetal_AddWall-01.png|240px]]
 * 8) Add some more walls
 * 9) Select the tray's upper outside edges  [[Image:SheetMetal_AddWall-08.png|240px]]
 * 10) Press the  button or use the keyboard shortcut:   [[Image:SheetMetal_AddWall-09.png|240px]]
 * 11) The walls are a bit too long (but nicely trimmed) and so the length property has to be set to a lower value [[Image:SheetMetal_AddWall-10.png|240px]]
 * 12) If you like the folds swing outward set the invert value to true [[Image:SheetMetal_AddWall-11.png|240px]]

Done!