PartDesign Chamfer

Description
The PartDesign Chamfer command creates chamfers on the selected edges of an object. It adds a Chamfer object to the document with its corresponding representation in the Tree view.

Add a chamfer

 * 1) Make sure the correct body is active. If required double-click it in the Tree view.
 * 2) There are several ways to select the edges to chamfer:
 * 3) * Select one or more edges of the active Body individually.
 * 4) * Select one or more faces of the active Body to select all their edges.
 * 5) * Select a feature (usually the last feature) of the active Body to select all its edges.
 * 6) For a chain of tangentially connected edges only a single edge needs to be selected, the chamfer will propagate along the chain.
 * 7) There are several ways to invoke the Chamfer command:
 * 8) * Press the button.
 * 9) * Select the option from the menu.
 * 10) If there was no active Body, and there are two or more bodies in the document, the  dialog will open prompting you to select one.
 * 11) The  task panel opens. See Options for more information.
 * 12) Press the  button to finish the command.

Edit a chamfer

 * 1) Do one of the following:
 * 2) * Double-click the Chamfer object in the Tree view
 * 3) * Right-click the Chamfer object in the Tree view and select from the context menu.
 * 4) The  task panel opens. See Options for more information.
 * 5) Press the  button to finish the command.

Options

 * Press the button to start selecting additional edges and faces in the 3D view.
 * To select all remaining edges do the following:
 * If required press the button.
 * Use the ++ shortcut, or right-click the list and select from the context menu.
 * To remove edges do one of the following:
 * Press the button to start deselecting edges and/or faces in the 3D view. Selected elements are highlighted in purple.
 * Select one or more elements in the list and press the key.
 * Select one or more elements in the list, right-click the list, and select from the context menu.
 * : Choose a chamfer type:
 * : One distance is used to place both chamfer edges.
 * : Two distances are used to place the chamfer edges.
 * : A distance is used to place one chamfer edge, the placement of the other chamfer edge is defined by the angle of the chamfer.
 * Press the button to flip the direction of the chamfer (deactivated for ).
 * Set the of the chamfer.
 * Set the of the chamfer (only available if  is selected).
 * Set the of the chamfer (only available if  is selected).
 * Check the checkbox to select all edges. This deactivates the selection list and the related buttons.

Properties
See also: Property editor.

A PartDesign Chamfer object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

Data

 * : Base. Sub-link to the parent feature's list of selected edges and faces.
 * : Support Transform. "Include the base additive/subtractive shape when used in pattern features.
 * If disabled, only the dressed part of the shape is used for patterning. Default:.


 * : Add Sub Shape.
 * : Base Feature. Link to the parent feature.
 * : _Body. Hidden link to the parent body.


 * : Chamfer Type. "Type of chamfer". (default),.
 * : Size. "Size of chamfer". Default:.
 * : Size2. "Second size of chamfer". Default:.
 * : Angle. "Angle of chamfer". Default:.
 * : Flip Direction. "Flip direction". Default:.
 * : Use All Edges. "Chamfer all edges if, else use only those edges in Base property.
 * If, then this overrides any edge changes made to the Base property or in the dialog". Default:.


 * : "Refine shape (clean up redundant edges) after adding/subtracting". Default:.

Known issues
See PartDesign Fillet.