PartDesign Chamfer

Description
The PartDesign Chamfer command creates chamfers on the selected edges of an object. It adds a Chamfer object to the document with its corresponding representation in the Tree view.

Add a chamfer

 * 1) Optionally activate the Body to chamfer.
 * 2) There are several ways to select edges to chamfer:
 * 3) * Select one or more edges of the Body individually.
 * 4) * Select one or more faces of the Body to select all their edges.
 * 5) * Select a feature (usually the last feature) of the Body to select all its edges.
 * 6) For a chain of tangentially connected edges only a single edge needs to be selected, the chamfer will propagate along the chain.
 * 7) There are several ways to invoke the Chamfer command:
 * 8) * Press the button.
 * 9) * Select the option from the menu.
 * 10) If there is no active Body, and there are two or more Bodies in the document, the  dialog will open and prompt you to activate one. If there is a single Body it will be activated automatically.
 * 11) The  task panel opens. See Options for more information.
 * 12) Press the  button to finish the command.

Edit a chamfer

 * 1) Do one of the following:
 * 2) * Double-click the Chamfer object in the Tree view
 * 3) * Right-click the Chamfer object in the Tree view and select from the context menu.
 * 4) The  task panel opens. See Options for more information.
 * 5) Press the  button to finish the command.

Options

 * To add edges do one of the following:
 * Press the button to start selecting edges and/or faces in the 3D view.
 * To select all remaining edges do the following:
 * If required press the button.
 * Use the ++ keyboard shortcut, or right-click the list and select from the context menu.
 * To remove edges do one of the following:
 * Press the button to start deselecting edges and/or faces in the 3D view. Selected elements are highlighted in purple.
 * Select one or more elements in the list and press the key, or right-click the list and select  from the context menu.
 * Specify a chamfer :
 * : One distance is used to place both chamfer edges.
 * : Two distances are used to place the chamfer edges.
 * : A distance is used to place one chamfer edge, the placement of the other chamfer edge is defined by the angle of the chamfer.
 * Press the button to flip the direction of the chamfer (deactivated for ).
 * Set the of the chamfer.
 * Set the of the chamfer (only available if  is selected).
 * Set the of the chamfer (only available if  is selected).
 * Check the checkbox to select all edges of the previous feature. This deactivates the selection list and the related buttons.

Properties
See also: Property editor.

A PartDesign Chamfer object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

Data

 * : Link to the selected edges and faces of the parent feature. Can be a link to only the parent feature if is.
 * : If the chamfered shape of the additive/subtractive parent feature will be used when the chamfer object is included in a pattern, else only the shape of the chamfer itself will be used. Default:.
 * : Link to the parent feature.
 * : Link to the parent body.
 * : Link to the parent body.


 * : The chamfer type: (default),  or.
 * : The first chamfer distance. Default:.
 * : The second chamfer distance. Only used if  is . Default:.
 * : The chamfer angle. Only used if  is . Default:.
 * : If the direction of the chamfer is flipped. Not used if  is . Default:.
 * : If all edges of the feature are chamfered, and the edges specified by  are ignored. Default:.


 * : If redundant edges are removed from the result of the operation. The default value is determined by the  preference. See PartDesign Preferences.

Known issues
See PartDesign Fillet.