PartDesign SubShapeBinder

Description
The PartDesign SubShapeBinder tool creates a shape binder referencing geometry from one or more parent objects. A SubShapeBinder is typically used inside a PartDesign Body to reference geometry outside the Body. Using external geometry directly in a Body is not allowed and will lead to out of scope errors. But a SubShapeBinder can also be used without being nested in a Body.

A SubShapeBinder will track the relative placement of the referenced geometry, which is useful in the context of creating assemblies, but on top of that also has its own placement.

The referenced geometry can consist of one or multiple elements. Each element can be an individual object (for example a PartDesign Body), a subobject (for example a Part Box inside a Std Part, or a sketch or feature inside a Body), or a subelement (a face, edge or vertex). Which geometry should be selected depends on the intended purpose of the SubShapeBinder. For a Boolean operation you would need to select a solid. For a Pad operation a face, a sketch or a planar wire can be used. And to attach a sketch sublements such as three vertices can be selected. Elements can belong to different parent objects, and can even belong to the Body the SubShapeBinder is nested in. Because a SubShapeBinder is Link-based the referenced geometry can also belong to an external document.





Same document

 * 1) If there are multiple Bodies in the document: optionally activate the Body the SubShapeBinder should be nested in.
 * 2) Select the required geometry. Subelements can only be selected in the 3D view.
 * 3) There are several ways to invoke the tool:
 * 4) * Press the button.
 * 5) * Select the option from the menu.
 * 6) The SubShapeBinder is created.
 * 7) If there is only one Body in the document the SubShapeBinder is automatically added to it and the Body is activated. If this is the case and the SubShapeBinder should not be nested, it can be dragged out of the Body and dropped onto the [[Image:Document.svg|16px]] document node in the Tree view.

External document

 * 1) If required open the source document (the external document) and the target document. Both documents must have been saved at least once.
 * 2) If there are multiple Bodies in the target document: optionally activate the Body the SubShapeBinder should be nested in.
 * 3) Select the required geometry in the source document. Subelements can only be selected in the 3D view.
 * 4) Switch to the target document by clicking its tab in the Main view area.
 * 5) Invoke the tool as described above.

Start with empty SubShapeBinder

 * 1) Follow the instructions described under Same document above but without selecting geometry.
 * 2) An empty SubShapeBinder is created.
 * 3) Select the required geometry. Subelements can only be selected in the 3D view.
 * 4) In the Tree view drag and drop the selection onto the SubShapeBinder.
 * 5) Optionally add more geometry in the same manner.
 * 6) To replace already referenced geometry hold down  during the drag and drop operation.

Properties
A PartDesign SubShapeBinder object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

Data

 * : support for the geometry.
 * : if it is it will fuse the solid linked shapes.
 * : if it is it will created a face for the linked wires.
 * : if it is it will claim the linked objects as children in the tree view.
 * : if it is it will enable relative sub-object linking.
 * : binding mode,, ,.
 * : if it is it will enable partial loading of the objects.
 * : container object of this binder object.
 * : if redundant edges will be removed (for example after a boolean operation).
 * : version of this type of object.
 * : version of this type of object.


 * : unity matrix of this object.


 * : 2D offset to apply. If Offset = 0, then no offset is applied. If Offset < 0, then the offset is applied inward.
 * : Join method of offsetting non-tangent joints. The method can be, or.
 * : If, a face is made between the new wire and the original wire. See also the property.
 * : Affects the way open wires are processed. If, an open wire is made. If , a closed wire is made from a double-sided offset, with rounds around open vertices.
 * : Affects the way compounds are processed. If, all children are processed independently. If , and children are edges and wires, the children are offset in a collective manner.

Links

 * New Sublink Link Feature, usage explanation with video.