PartDesign SubShapeBinder/fr

Description
PartDesign Sous forme liée importe un élément d'un autre corps dans le Corps actif. Il peut prendre la forme de, ou être "lié" à un ou plusieurs objets ou sous-éléments (bords ou faces) d'un autre objet.

Il peut également se lier à des objets imbriqués dans des Std Parts et il suivra le placement relatif de ces fonctions. Ceci est utile dans le contexte de la création d'Assemblages car souvent, l'utilisateur doit référencer des PartDesign Fonctionnalités qui sont déjà correctement placées dans un autre sous-assemblage.

The referenced geometry can consist of one or multiple elements. Each element can be an individual object (for example a PartDesign Body), a subobject (for example a Part Box inside a Std Part, or a sketch or Feature inside a Body), or a subelement (a face, edge or vertex). Which geometry should be selected depends on the intended purpose of the SubShapeBinder. For a Boolean operation you would need to select a solid. For a Pad operation a face, a sketch or a planar wire can be used. And for the external geometry in a sketch, or to attach a sketch, any combination of subelements may be appropriate. Elements can belong to different parent objects, and can even belong to the Body the SubShapeBinder is nested in. Because a SubShapeBinder is Link-based the referenced geometry can also belong to an external document.





Same document

 * 1) If there are multiple Bodies in the document: optionally activate the Body the SubShapeBinder should be nested in.
 * 2) Select the required geometry. Subelements can only be selected in the 3D view.
 * 3) There are several ways to invoke the tool:
 * 4) * Press the button.
 * 5) * Select the option from the menu.
 * 6) The SubShapeBinder is created.
 * 7) If there is only one Body in the document the SubShapeBinder is automatically added to it and the Body is activated. If this is the case and the SubShapeBinder should not be nested, it can be dragged out of the Body and dropped onto the [[Image:Document.svg|16px]] document node in the Tree view.

External document

 * 1) If required open the source document (the external document) and the target document. Both documents must have been saved at least once.
 * 2) If there are multiple Bodies in the target document: optionally activate the Body the SubShapeBinder should be nested in.
 * 3) Select the required geometry in the source document. Subelements can only be selected in the 3D view.
 * 4) Switch to the target document by clicking its tab in the Main view area.
 * 5) Invoke the tool as described above.

Start with empty SubShapeBinder

 * 1) Follow the instructions described under Same document above but without selecting geometry.
 * 2) An empty SubShapeBinder is created.
 * 3) Select the required geometry. Subelements can only be selected in the 3D view.
 * 4) In the Tree view drag and drop the selection onto the SubShapeBinder. If you have selected subelements their parent objects are highlighted in the Tree view, indicating the objects to be dragged.
 * 5) Optionally add more geometry in the same manner.
 * 6) To replace already referenced geometry hold down  during the drag and drop operation.

PartDesign SubShapeBinder vs. PartDesign ShapeBinder
The PartDesign SubShapeBinder tool and the PartDesign ShapeBinder tool are quite similar. Their names are somewhat confusing as both can reference whole objects and subelements.

The main differences are:
 * Editing a PartDesign ShapeBinder is easier. Double-clicking the object in the Tree view will open a task panel.
 * A PartDesign ShapeBinder can either reference a single whole object, or subelements belong to a single parent object. A PartDesign SubShapeBinder does not have these restrictions.
 * Only PartDesign SubShapeBinders can reference geometry from an external file.
 * A PartDesign SubShapeBinder always tracks the relative placement of the referenced geometry. For a PartDesign ShapeBinder this behavior is optional through its property.
 * Only PartDesign SubShapeBinders support 2D offsetting.

Propriétés
PartDesign Sous forme liée est dérivée de Part Feature (classe ). En plus des propriétés répertoriées dans Part Feature, les propriétés suivantes sont disponibles dans l'Éditeur de propriétés.

Données

 * : support de la géométrie.
 * : si, fusion les formes liées solides.
 * : si, création d'une face pour les polylignes liées.
 * : si, donnera les objets liés en tant qu'enfants dans la vue en arborescence.
 * : si, cela permettra d'établir des liens relatifs entre les sous-objets.
 * : mode de liaison,, ,.
 * : si, cela permettra le chargement partiel des objets.
 * : objet conteneur de cet objet liant.
 * : version de ce type d'objet.
 * : Part TopoShape de cet objet.


 * : matrice d'unité de cet objet.


 * : 2D offset to apply. If Offset = 0, then no offset is applied. If Offset < 0, then the offset is applied inward.
 * : Join method of offsetting non-tangent joints. The method can be, or.
 * : If, a face is made between the new wire and the original wire. See also the property.
 * : Affects the way open wires are processed. If, an open wire is made. If , a closed wire is made from a double-sided offset, with rounds around open vertices.
 * : Affects the way compounds are processed. If, all children are processed independently. If , and children are edges and wires, the children are offset in a collective manner.

Liens

 * New Sublink Link Feature, explication d'utilisation avec vidéo.