PartDesign Draft

Description
The PartDesign Draft command creates angular draft on the selected faces of an object. It adds a Draft object to the document with its corresponding representation in the Tree view.

Add a draft

 * 1) Optionally activate the Body to draft (by double clicking the Tree view item).
 * 2) Select one or more face(s) on the active Body.
 * 3) There are several ways to invoke the Draft tool:
 * 4) * Press the button.
 * 5) * Select the option from the menu.
 * 6) The Draft parameters dialog will open in the Task panel and allows to set several options.
 * 7) Click  to validate.


 * Remember:
 * Since there must be at least one face for the feature, the last remaining face in the list cannot be removed.

Edit a draft

 * 1) There are two ways to reopen the Draft dialog to edit a Draft:
 * 2) * Double-click on the Draft item in the Tree view
 * 3) * Right-click on the Draft item in the Tree view and select from the context menu.
 * 4) The Draft parameters dialog will open in the Task panel and allows to set several options.
 * 5) Click  to validate.

Options

 * : Set the Draft angle either by entering a value or by clicking on the up/down arrows. The applied draft angle is shown in real time.
 * : Add faces to the selection by pressing the button and selecting more faces.
 * : Choose a way to remove faces from the selection:
 * Select each face in the list of the dialog and press the key or right-click in the list and select  from the context menu.
 * Press the button. All faces being previously selected are highlighted in purple. Select each face to be removed.


 * : Set the the neutral plane by pressing the button and selecting the plane that must not change dimensionally. The change is made in real time.
 * : Set the the pull direction by pressing the button, then select an edge. Pull Direction is only effective if the Neutral Plane has been set. Results can be unpredictable.
 * : invert the pull direction by checking the checkbox. This will toggle the draft between positive and negative angles.

Special cases
The Draft tool will only function on faces that are normal to each other. If there are any tangential faces attached to the face you wish to apply draft to, it will fail. A common cause of failure is attempting to apply draft to a face that already has a fillet or chamfer applied to it. In this case, remove the tangential surface, apply the draft as need, then re-apply the fillet or chamfer.

Properties
See also: Property editor.

A PartDesign Draft object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

Data

 * : Angle. Default:.
 * : Reversed. Default:.
 * : Base. Sub-link to the parent feature's list of selected edges and faces.
 * : Support Transform. "Include the base additive/subtractive shape when used in pattern features.
 * If disabled, only the dressed part of the shape is used for patterning. Default:.


 * : Add Sub Shape.
 * : Base Feature. Link to the parent feature.
 * : _Body. Hidden link to the parent body.


 * : Neutral Plane. Sub-link to the parent feature's list containing the neutral plane.
 * : Pull Direction.


 * : "Refine shape (clean up redundant edges) after adding/subtracting". Default:.