SheetMetal AddBase

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    SheetMetal AddBase.svg SheetMetal AddBase

    Menu location
    SheetMetal → Make Base Wall
    Workbenches
    SheetMetal
    Default shortcut
    C B
    Introduced in version
    -
    See also
    None

    Description

    The SheetMetal AddBase.svg SheetMetal AddBase command creates a SheetMetal base object from a sketch.

    From an open contour it creates a prismatic profile:

    SheetMetal AddBase-01.png Button right.svg SheetMetal AddBase-02.png


    From a closed outline it creates a base plate (blank):

    SheetMetal AddBase-03.png Button right.svg SheetMetal AddBase-04.png

    Usage

    Profile

    1. Select an open contour Workbench Sketcher.svg sketch.
    2. Activate the SheetMetal AddBase.svg SheetMetal AddBase command using one of the following:
      • The SheetMetal AddBase.svg Make Base Wall button.
      • The SheetMetal → SheetMetal AddBase.svg Make Base Wall menu option.
      • The keyboard shortcut: C then B.
    3. Adjust the profile's parameters by editing the corresponding values in the Property editor:
      • The property Datalength for the profile length,
      • The property Datathickness for the profile thickness,
      • The property Dataradius for the inner radius of the bends.

    Plate

    1. Select a closed outline Workbench Sketcher.svg sketch.
    2. Activate the SheetMetal AddBase.svg SheetMetal AddBase command (see above).
    3. Adjust the plate's parameter by editing the corresponding value in the Property editor:
      • The property Datathickness for the thickness of the plate.
    (The properties Datalength and Dataradius are not used for plates.)

    Properties

    See also: Property editor.

    A SheetMetal BaseBend object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

    Data

    Base

    • DataLabel (String): Default value: BaseBend (+ a sequential number for second and following items).
      The user editable name of this object, it may be any arbitrary UTF8 string.
    • Data (hidden)Base Feature (Link): Base Feature. Link to the parent feature.
    • Data (hidden)_Body (LinkHidden): Hidden link to the parent body.

    Parameters

    • DataBend Side (Enumeration): "Relief Type". Outside (default), Inside, Middle.
    • DataBend Sketch (Link): "Wall Sketch object". Link to the profile/outline sketch.
    • DataMid Plane (Bool): "Extrude Symmetric to Plane".
      false (default), the profile extends to one side of the sketch plane,
      true, the profile extends symmetrically to both sides of the sketch plane.
    • DataReverse (Bool): "Reverse Extrusion Direction". Default: false.
    • Datalength (Length): "Length of wall". Default: 100,00 mm.
    • Dataradius (Length): "Bend Radius". Default: 1,00 mm.
    • Datathickness (Length): "Thickness of sheetmetal". Default: 1,00 mm.