Draft PolarArray
Draft PolarArray |
Menu location |
---|
Modification → Array tools → Polar array |
Workbenches |
Draft |
Default shortcut |
None |
Introduced in version |
0.19 |
See also |
Draft OrthoArray, Draft CircularArray, Draft PathArray, Draft PathLinkArray, Draft PointArray, Draft Clone |
Description
The Draft PolarArray tool creates an array from a selected object placing the copies along a circumference.
This tool can be used on any object that has a Part TopoShape, meaning 2D shapes created with the Draft Workbench, but also 3D solids created with other workbenches, for example, Part, PartDesign, or Arch. It can also create App Links instead of simple copies.
- To create orthogonal or circular arrays, use the corresponding OrthoArray and CircularArray tools.
- To position copies along a path use PathArray or PathLinkArray.
- To position copies at specified points use PointArray or PointLinkArray.
- To create copies and manually place them use Move or Rotate.
- To create exact copies and manually place or scale them, use Clone or Std LinkMake.
A polar array of an object.
Usage
- Select the object that you wish to array.
- Press the Polar array button. If no object is selected, you will be invited to select one before proceeding.
- The task panel is launched where you can select the polar angle, the number of elements, and the center of the axis of rotation.
- You can click on the 3D view to simultaneously set the position of the center of rotation, and complete the command. Otherwise, just press Enter or the OK button to complete the operation.
Options
- Enter the Polar angle to specify the total angle of the array. The angle is positive in the counter-clockwise direction.
- Enter the Number of elements. Must be at least
2
. The maximum that can be entered in the task panel is99
, but higher values are possible by changing the DataNumber Polar property of the array. - Pick a point in the 3D view or type coordinates for the Center of rotation. The rotation axis of the array will pass through this point. It is advisable to move the pointer out of the 3D view before entering coordinates.
- Press the Reset point button to reset the Center of rotation to the origin.
- If the Fuse checkbox is checked overlapping elements in the array are fused. This does not work for Link arrays.
- If the Link array checkbox is checked a Link array instead of a regular array is created. A Link array is more efficient because its elements are App Link objects.
- Press Esc or the Cancel button to abort the command.
Notes
- The default rotation axis for the array is the positive Z axis. This can be changed by editing its DataAxis property.
- A Draft PolarArray can be turned into a Draft OrthoArray or a Draft CircularArray by changing its DataArray Type property.
- A Link array cannot be turned into a regular array or vice versa. The type of array must be decided at creation time.
Properties
See Draft OrthoArray.
Scripting
See also: Autogenerated API documentation and FreeCAD Scripting Basics.
Parametric array
To create a parametric polar array use the make_array
method (introduced in version 0.19) of the Draft module. This method replaces the deprecated makeArray
method. The make_array
method can create Draft OrthoArrays, Draft PolarArrays and Draft CircularArrays. For each array type one or more wrappers are available.
The main method:
array = make_array(base_object, arg1, arg2, arg3, arg4=None, arg5=None, arg6=None, use_link=True)
The wrapper for polar arrays is:
array = make_polar_array(base_object,
number=5, angle=360, center=App.Vector(0, 0, 0),
use_link=True)
base_object
is the object to be arrayed. It can also be theLabel
(string) of an object in the current document.number
is the number of elements in the pattern, including the original object.angle
is the angle of the polar arc in degrees.center
is the vector that defines the center of the pattern.- If
use_link
isTrue
the created elements are App Links instead of regular copies. array
is returned with the created array object.
Example:
import FreeCAD as App
import Draft
doc = App.newDocument()
tri = Draft.make_polygon(3, 600)
center = App.Vector(-1600, 0, 0)
array = Draft.make_polar_array(tri, 8, 270, center)
doc.recompute()
Non-parametric array
To create a non-parametric polar array use the array
method of the Draft module. This method returns None
.
array(objectslist, center, angle, number)
Example:
import FreeCAD as App
import Draft
doc = App.newDocument()
tri = Draft.make_polygon(3, 600)
center = App.Vector(-1600, 0, 0)
Draft.array(tri, center, 270, 8)
doc.recompute()
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- Context menu:
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