Arkusz Blachy: Utwórz ściankę
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SheetMetal AddWall |
Menu location |
---|
SheetMetal → Make Wall |
Workbenches |
SheetMetal |
Default shortcut |
W |
Introduced in version |
- |
See also |
None |
Opis
Polecenie Dodaj ścianę tworzy obrzeża na wybranych krawędziach płyty bazowej. Poprzez zmianę właściwości DANEkąt obrzeża można je przekształcić w półokrągłości.
A flange consists of a 90° cylindrical bend and a planar strip (wall).
Two selected edges → two flanges
Resetting the DANEangle property to about 180° in a second step will create a hem instead.
Two selected edges → two hems
Usage
- Select one or more edge(s) of a base plate.
- Activate the SheetMetal AddWall command using one of the following:
- The Make Wall button.
- The SheetMetal → Make Wall menu option.
- The keyboard shortcut: W.
Notes
To create a base plate use a closed 2D outline - preferably a Sketch - with the Make Base Wall command.
Alternatively a base plate (blank) can be created with commands from the Part Workbench or PartDesign Workbench.
To create a blank with the Part Workbench:
- Create a solid using either:
- Part Box.
- Part Extrude from:
- A Draft Rectangle.
- A Draft Wire.
- A Sketch.
- Make sure one the dimensions of the Box or the extrusion distance equals the sheet metal thickness.
To create a blank with the PartDesign Workbench:
- Create a solid using either:
- Additive Box.
- PartDesign Pad from a Sketch.
- Make sure one the dimensions of the Box or the DANELength property of the Pad equals the sheet metal thickness.
If you start with a PartDesign Body, you can mix SheetMetal features with PartDesign features such as PartDesign Pocket or PartDesign Hole.
Properties
See also: Property editor.
A SheetMetal Bend object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties and its label has a default value:
Data
Base
- DANELabel (
String
): Default value:Bend
(+ a sequential number for second and following items).
The user editable name of this object, it may be any arbitrary UTF8 string. - DANE (hidden)Base Feature (
Link
): Base Feature. Link to the parent feature. - DANE (hidden)_Body (
LinkHidden
): Hidden link to the parent body.
Parameters
- DANEBend Type (
Enumeration
): "Bend Type".Material Outside
(default),Material Inside
,Thickness Outside
,Offset
. - DANELength Spec (
Enumeration
): "Type of Length Specification".Leg
(default),Outer Sharp
,Inner Sharp
,Tangential
. introduced in version 1.0 - DANEangle (
Angle
): "Bend Angle". Default angle:90,00°
. - DANEbase Object (
LinkSub
): "Base Object". Link to the planar face to receive a bend. - DANEgap1 (
Distance
): "Gap from Left side". Default:0,00 mm
. - DANEgap2 (
Distance
): "Gap from Right side". Default:0,00 mm
. - DANEinvert (
Bool
): "Invert Bend Direction". Default:false
. - DANElength (
Length
): "Length of Wall". Default:10,00 mm
. - DANEradius (
Length
): "Bend Radius". Default:1,00 mm
.
Parameters Ex
- DANEAuto Miter (
Bool
): "Enable Auto Miter". Default:true
. - DANEextend1 (
Distance
): "Extend from Left Side". Default:0,00 mm
. - DANEextend2 (
Distance
): "Extend from Right Side". Default:0,00 mm
. - DANEkfactor (
FloatConstraint
): "Location of Neutral Line. Caution: Using ANSI standards, not DIN.".
Default:0,50
. K factor (also known as neutral factor) for the bend. Used to calculate bend allowance when unfolding. - DANEmax Extend Dist (
Length
): "Auto Miter maximum Extend Distance". Default:5,00 mm
. - DANEmin Gap (
Length
): "Auto Miter Minimum Gap". Default:5,00 mm
. - DANEmiterangle1 (
Angle
): "Bend Miter Angle from Left Side". Default angle:0,00°
. - DANEmiterangle2 (
Angle
): "Bend Miter Angle from Right Side". Default angle:0,00°
. - DANEoffset (
Distance
): "Offset Bend". Default:0,00 mm
. - DANEunfold (
Bool
): "Shows Unfold View of Current Bend". Default:false
true
unfolds the bend.
Parameters Ex2
- DANESketch (
Link
): "Sketch Object". - DANEsketchflip (
Bool
): "Flip Sketch Direction". Default:false
. - DANEsketchinvert (
Bool
): "Invert Sketch Start". Default:false
.
Parameters Ex3
- DANELength List (
FloatList
): "Length of Wall List". Default:[10,00]
. - DANEbend AList (
FloatList
): "Bend Angle List". Default:[90,00]
.
Parameters Relief
- DANERelief Factor (
Float
): "Relief Factor". Default:0,70
. - DANEUse Relief Factor (
Bool
): "Use Relief Factor". Default:false
. - DANEmin Relief Gap (
Length
): "Minimum Gap to Relief Cut". Default:1,00 mm
. - DANErelief Type (
Enumeration
): "Relief Type".Rectangle
(default),Round
. Enabled only when a gap value is set. - DANEreliefd (
Length
): "Relief Depth". Default:1,00 mm
. Enabled only when a gap value is set. - DANEreliefw (
Length
): "Relief Width". Default:0,80 mm
. Enabled only when a gap value is set.
Example
A simple tray
Preparation
This tray is made of a rectangular blank with walls added to its outline edges. And so one outline sketch for the blank has to be prepared in advance.
Just a rectangular outline
Workflow
- Create a blank
- Select the outline sketch
- Press the Make Base Wall button
or use the keyboard shortcut: C then F
(The blank is padded in z direction
- Select the outline sketch
- Add walls to the outline edges
- Select the blank's outline edges
- Press the Make Wall button
or use the keyboard shortcut: W
- If the fold is 90° down set the value of invert property to true to reverse the direction (and length to a lower value for smaller walls)
- Select the blank's outline edges
- Add some more walls
- Select the tray's upper outside edges
- Press the Make Wall button
or use the keyboard shortcut: W
- The walls are a bit too long (but nicely trimmed) and so the length property has to be set to a lower value
- If you like the folds swing outward set the invert value to true
- Select the tray's upper outside edges
Done!